Laser CAM

Cutting Condition

There are three condition based on which a sheet is cut.

Choose cutting condition by - This setting is to define how the cutting condition will be selected. The options include Maximum segment length, Average segment length and Area. The area is the conventional setting deciding on the Trumpf rules, and Max and average segments decide accordingly.

Switch to slower cutting condition when approach is constrained - The laser head switches to a slow speed cutting situation when the sheet geometry for the approach is complex.

Process for open polylines - When open polylines are found in a part, depending on which option is selected, Cut will process the polyline accordingly. The options includes Cut, Mark, None and Based on layer.

Cut/Mark open polylines - The option is to cut or mark open polylines backwards. This setting will only apply if cut or mark is set for the process for open polylines.

Mark forming foorprint - When a counter sink situation is detected by Cut, it automatically moves the outer circle to the layer Forming footprint. If this option is checked, geometry in Form footprint layer will be marked.

Stitch cutting threshold distance (0 = disable) - This option is to define the maximum distance between two cuts which will be considered for stitch cut.

Dynamics - Dynamics dropdown menu includes Normal, High and Reduced.

Pierce settings

Allow approach that is more than 0.5 distance to the opposite side - This option is to define whether an approach is allowed to cover more than the distance to the opposite side.

Corner Processing

Rounding tolerance (distance of corner from rounding tip) - This option is to define the maximum distance allowed from the corner to the rounding tip as shown in the image below. The distance of the corner from the rounding tip is directly proportional to the rounding radius. Based on the value entered here, Cut will select the rounding radius in the range of min. and max. If selecting the smallest radius does not bring this distance within the tolerance value, then rounding will not be applied (looping or cooling might be applied).

Maximum distance of corner from outermost point on loop - This option is to define the maximum extension of the loop from the corner. The loop extension is directly proportional to radius. At a sharp corner, if selecting smallest radius does not bring this distance within the value entered here, looping will not be applied (rounding or cooling might still be applied).

Twinline

Twinline processing strategy - This drop-down is to define the twinline strategy to be used.

Partwise - The cuts are made partwise. Suitable for thick sheets where there is no rick of tipping contours.

Partwise-Safe - The cuts are made partwise, but preparatory cuts are made into adjacent parts. Suitable for thin sheets where parts could tip.

Twinline Islands Outer - Twinline edges are cut first, followed by any islands created between parts and then outer contour.

Use TIO strategy of there are no islands - The software will always choose Twinline Islands Outer strategy, if there are no islands created in the twinline block. This option is checked by default.

Scarp cutting

Scrap grid width - This is the width of each cell in the grid that is created by the tooling. The value entered here must be such that the resultant square is guaranteed to fall through the slats irrespective of its position.

Approach length for separating cuts - This is the length of the approached desired on scrap cuts.

Vaporization

Vaporize - This setting will control if vaporization must be done or not. And, if it must be done, which portions of the laser cutting path must be vaporized. None - No vaporization Pierce - Only the pierce points will be vaporized Pierce & approach - Pierce and approach portions of the laser cut path will be vaporized. Full path - The entire cutting path including the pierce, approach and contour will be vaporized.

Pierce point vaporization circle radius - If a value greater than zero is entered here, the software will move the laser head in a small circle around the pierce point with the vaporizing laser on (circle vaporization). The value decides the radius of this circle. If this value is zero, vaporizing laser will be turned on exactly on top of the piercing point and then immediately turned off (point vaporization).

Vaporize marking - This option is to enable or disable vaporization. Note that laser text markings which are etched using TC_WRITE macro are never vaporized.

When these settings are modified, there will be no visible change in Cut UI except that the NC-code icon will get re-enabled if it was disabled earlier. This is because these settings have an impact on code generation. Generated vaporizing code for different cuts is described in the table below.

Cut	Behaviour
Laser Cut	This is the usual cut item to cut a contour of the part. If Vaporize = Full path, the entire contour, including pierce and approach will be vaporized. However, during the vaporizing pass, beam compensation is turned off. It is not necessary that the cut is performed immediately after vaporization. If a contour has more than 1 microjoint and hence multiple lasers cut pieces, all the cut pieces of that contour are vaporized first. Then, the cutting of the contour starts. This vaporization sequence is called contour-wise, as each contour is vaporized before it is cut. This usually leads to efficient head movement. If Vaporize = Pierce & approach, Only the pierce point and approach path are vaporized first and at once following that, the laser head will reposition over the pierce point and start actual cutting. For this vaporizing option and for Vaporize = Pierce, the pierce and approach are always vaporized just before executing the cut. This type of vaporization sequence is called cut-wise, as each cut piece is vaporized before it is cut. Behaviour of Vaporize = Pierce, is like the above except that only the pierce points are vaporized. If Vaporize = None, there is no change in generated code.
Scrap Cut	If Vaporize = Full path, the vaporizing and cutting sequence would be as follows: - The entire scrap grid will be vaporized first, in the same way as it would be cut. - The contour along with its pierce and approach will be vaporized. - The scrap grid will be cut. - The contour will be cut. So, the grid and the contour, both are vaporized and then they are cut. If Vaporize = Pierce & approach or Pierce, the pierce and approach segments for scrap and contour will be vaporized just before they are cut.
Sheet Cut	A sheet cut will always be vaporized just before it is cut.
Flyline Cut	These cuts are never vaporized, irrespective of the vaporize settings.
Point Cut	This will be vaporized just before it is cut.

Cut

Behaviour

Laser Cut

This is the usual cut item to cut a contour of the part.
If Vaporize = Full path, the entire contour, including pierce and approach will be vaporized. However, during the vaporizing pass, beam compensation is turned off. It is not necessary that the cut is performed immediately after vaporization. If a contour has more than 1 microjoint and hence multiple lasers cut pieces, all the cut pieces of that contour are vaporized first. Then, the cutting of the contour starts. This vaporization sequence is called contour-wise, as each contour is vaporized before it is cut. This usually leads to efficient head movement.

scraplasercut

If Vaporize = Pierce & approach, Only the pierce point and approach path are vaporized first and at once following that, the laser head will reposition over the pierce point and start actual cutting. For this vaporizing option and for Vaporize = Pierce, the pierce and approach are always vaporized just before executing the cut. This type of vaporization sequence is called cut-wise, as each cut piece is vaporized before it is cut.

Behaviour of Vaporize = Pierce, is like the above except that only the pierce points are vaporized.

If Vaporize = None, there is no change in generated code.

Scrap Cut

If Vaporize = Full path, the vaporizing and cutting sequence would be as follows:

- The entire scrap grid will be vaporized first, in the same way as it would be cut.

- The contour along with its pierce and approach will be vaporized.

- The scrap grid will be cut.

- The contour will be cut.

So, the grid and the contour, both are vaporized and then they are cut. If Vaporize = Pierce & approach or Pierce, the pierce and approach segments for scrap and contour will be vaporized just before they are cut.

Sheet Cut

A sheet cut will always be vaporized just before it is cut.

Flyline Cut

These cuts are never vaporized, irrespective of the vaporize settings.

Point Cut

This will be vaporized just before it is cut.

Laser Marking

Rules for adding one or more text markings on the part can be defined in Settings → Cut CAM → Profile CAM → Laser marking. In the table shown below, user can add multiple rules, each rule leading to placement of a single line of text.

Column	Description
Checkbox	You can enable or disable a rule using the checkbox in the first column.
Text	The text that must be inserted on the part. This text can contain following tokens that will be replaced with the corresponding value from Part info. These tokens are not case sensitive. $PARTNAME - Name of the part. $FILENAME - Name of the FX file. $ROOTFILE - Name of the original CAD file. $PARTID - Part identifier. $CUSTOMER - Customer. $AUTHOR - Author. $JOBNUMBER - Job number from Part→Info. These variables are indicated in a tooltip.
Height	This is the font height (from baseline to ascent line.) in mm or inch units. When inserting this text, it might be possible that there is not enough space to insert the text at prescribed font height. In such situations, Flux will automatically shrink the text size in steps of 10% until it is feasible to place it. This stepping down in currently allowed up-to 2mm. Minimum has been set to 2mm.
Orientation	This column determines the text orientation. Following values are possible: Horizontal - Text will be horizontal. Vertical - Text will be vertical. Along longer side: Text will be aligned with the longer side of the part. If the part is landscape, it will be horizontal and vertical if the part is portrait. Along shorter side: Text will be aligned with shorter side of the part (opposite of the above.) When adding two texts to the part, this and the previous option can be used together to minimize the risk of overlapping text. Along longest segment: Text will be aligned with the longest linear segment of the outer contour. In this case the text might not be axis aligned. Whether the text is placed horizontal, vertical or oblique, Flux will always orient the text such that the user finds the text in right direction when looking at the part from the side closest to the text. That is, horizontal text placed to bottom-center will run left-to-right and when placed to top-center will run right-to-left.
Horizontal pos	Horizontal alignment of text. Possible values are center, left & right. This setting is not relevant if Along longest segment is chosen as the required orientation.
Vertical pos	Vertical alignment of text. Possible values are center, bottom & top. This setting is not relevant if Along longest segment is chosen as the required orientation.

Column

Description

Checkbox

You can enable or disable a rule using the checkbox in the first column.

Text

The text that must be inserted on the part. This text can contain following tokens that will be replaced with the corresponding value from Part info. These tokens are not case sensitive.

$PARTNAME - Name of the part.

$FILENAME - Name of the FX file.

$ROOTFILE - Name of the original CAD file.

$PARTID - Part identifier.

$CUSTOMER - Customer.

$AUTHOR - Author.

$JOBNUMBER - Job number from Part→Info.

These variables are indicated in a tooltip.

Height

This is the font height (from baseline to ascent line.) in mm or inch units. When inserting this text, it might be possible that there is not enough space to insert the text at prescribed font height. In such situations, Flux will automatically shrink the text size in steps of 10% until it is feasible to place it. This stepping down in currently allowed up-to 2mm.

Minimum has been set to 2mm.

Orientation

This column determines the text orientation. Following values are possible:
Horizontal - Text will be horizontal.
Vertical - Text will be vertical.

Along longer side: Text will be aligned with the longer side of the part. If the part is landscape, it will be horizontal and vertical if the part is portrait.

Along shorter side: Text will be aligned with shorter side of the part (opposite of the above.) When adding two texts to the part, this and the previous option can be used together to minimize the risk of overlapping text.

Along longest segment: Text will be aligned with the longest linear segment of the outer contour. In this case the text might not be axis aligned. Whether the text is placed horizontal, vertical or oblique, Flux will always orient the text such that the user finds the text in right direction when looking at the part from the side closest to the text. That is, horizontal text placed to bottom-center will run left-to-right and when placed to top-center will run right-to-left.

Horizontal pos

Horizontal alignment of text. Possible values are center, left & right. This setting is not relevant if Along longest segment is chosen as the required orientation.

Vertical pos

Vertical alignment of text. Possible values are center, bottom & top. This setting is not relevant if Along longest segment is chosen as the required orientation.

When adding these marks, Flux always ensures that the added text does not collide with any part contour. For very tiny parts or parts with little open space, it will automatically scale down the font size by the required amount to fit the text inside the part and away from any holes.